Thin Solids
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When creating pads, pockets and
stiffeners, you can now add thickness to both sides of their profiles. The
resulting features are then called "thin solids". This task shows you how to add thickness to a pad. The method described here is also valid for pockets. To know how to obtain a thin solid from a stiffener, refer to the task Stiffener. |
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Open the GettingStarted1.CATPart document and quit the Sketcher. | ||
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1. | Click the Pad icon
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| 2. | Select Sketch.1 if not already done. | ||
| 3. | Check the option "Thick". This opens the whole Pad Definition dialog box. You can now define your thin pad using the options available in the Thin Pad frame. |
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The options for creating thin solids are not available when you select a surface as the element to be extruded. | ||
| 4. | Enter 18mm as Thickness1 's value, and click Preview to see the result. A thickness has been added to the profile as it is extruded. The profile is previewed in dotted line. |  |
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| 5. | Enter 10mm as Thickness2 's value, and click Preview to see the result. Material has been added to the other side of the profile. |  |
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| 6. | To add material equally to both sides of the
profile, check "Neutral fiber" and click Preview to see the
result. The thickness you defined for LIM 1 (18mm) is now evenly distributed: a thickness of 9mm has been added to each side of the profile. |
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This capability can be applied to several profiles contained in the same sketch. | ||
"Thin Pad" options let you extrude profiles from networks |
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| Using the "Thin Pad" options you can extrude profiles from networks. | |||
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| Thickness 1 and Thickness 2 are defined. |  |
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| Checking the "Merge Ends" option trims
extrusions to existing material.
Keep in mind that the creation order of the different elements constituting the profile never affects the resulting extrusion. |
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If you decide to use the options "Up to Plane" or "Up to Surface", the "Merge ends" capability is not available. | ||
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How Extrusions are Trimmed |
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| In the following example, the network goes beyond the edges of the part. | |||
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| Initial profile is made of two intersecting lines | The application trims extrusions to the faces of the pocket | ||
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