Creating Views via the Wizard

This task will show you how to create views using a wizard. These views are views that are generated automatically once the CATDrawing document is opened. These views can then be modified as if they had been manually created one after the other.

Before You Begin, make sure you customized the following settings:

Grid:
De-activate the Grid icon from the Tools toolbar (bottom right).

View names and scaling factors:
Go to Tools->Options -> Mechanical Design -> Drafting optionat the left of the dialog box, Layout tab) and check the View name and Scaling factor options.

3D colors inheritance
Go to Tools->Options->Mechanical Design->Drafting option (Generation tab) and un-check the 3D colors inheritance option.

Open the GenDrafting_part.CATPart document.

Start creating a new drawing (and this case, create an empty sheet).

Before You Begin

Make sure you select the projection mode you need. If you want to change the method you use as you pre-define your configurations, what you need to do is:

1. Right-click the sheet.
2. Select the Properties option from the displayed contextual menu.
The Properties dialog box appears with Projection Method options.
3. Check the Create projection view using first angle standard option.

Create projection views using first angle standard: Orthographic representation comprising the arrangement, around the principal view of an object, of some of all of the other five views of that object. With reference to the principal view, the other views are arranged as follows:
- the view from above is placed underneath
- the view from below is placed above
- the view from the left is placed on the right
- the view from the rear is placed on the left or on the right, as convenient.
(Ref. No. ISO 10209-2:1993)

Create projection views using third angle standard: Orthographic representation comprising the arrangement, around the principal view of an object, of some of all of the other five views of that object. With reference to the principal view, the other views are arranged as follows:
- the view from above is placed above
- the view from below is placed underneath
- the view from the left is placed on the left
- the view from the rear is placed on the left or on the right, as convenient.
(Ref. No. ISO 10209-2:1993)

1. Click the Drawing window, and click the Wizard icon

from the Views toolbar (Wizard subtoolbar).

2. Select the desired view configuration from the View Wizard (1/2) : Predefined Configurations dialog box.

In this case, ISO standard / First angle projection method is used and the following configurations are available:

front, bottom and left

front, bottom and right

front, top and left

front, top and right

projection and isometric

projection, rear and isometric

If you use the ANSI standard (Third angle projection method), in the dialog box the configuration symbol displayed

, as well as the configuration options will be different. To have the projection views linked to the main view click the

option.

You can can define the Minimum distance between each view. For this, enter the desired value in the modifiable field available in the View Wizard dialog box.

A preview is available:

	The main view corresponds to the view which any other view will be linked to. This main view can be either a front or an isometric view. It is squared in the green color. This is the view that will become the active view when you will generate the desired views. Any other view (front and/or isometric view) that can possibly become the main view is squared in the black color. To make a view become the main view, right-click this view and select the `Set as main view` option from the contextual menu.
	At any time, you can delete one view you inserted. For this, right-click the desired view and select the `Delete` option from the contextual menu.
	Once you generate the views, if you move the main view, all the children views will move accordingly. You can right-click one view and select the `Do not align` option from the contextual menu, if you need to move one child view independently from the mother view.

3. Click the NEXT> button from the View Wizard (1/2) : Predefined Configurations dialog box.

The View Wizard (2/2) : Arranging the Configuration dialog box is now displayed with a new set of view buttons:

	front view
	rear view
	top view
	bottom view
	left view
	right view
	isometric view
	clear preview

4. Click the Isometric View button

5. Position the isometric view onto the Preview window by dragging and clicking it as desired.

6. Click the FINISH button from the View Wizard (2/2) : Arranging the Configuration dialog box.

7. Select the CATPart document.

8. Click on the desired 3D part plane to be used as reference plane.

If the plane can be computed, the Oriented Preview of the 3D part appears as you move the cursor over the 3D part (planes).

The views now appear on the CATDrawing document: they are previewed in green frames and can be re-oriented thanks to the blue arrows that appear.

9. Go over the view frames with your cursor to have these views visualized.

10. Use the blue arrows to have the views re-oriented as desired and then go over the views with the cursor, if you need to check the preview of the other views.

For more details, see chapter called Before You Begin.

You can also modify the increment value using the green knob contextual menu. For this, right-click on the knob and select the desired option from the contextual menu. For more details, see chapter called Before You Begin.

11. Once you are satisfied, click on the sheet to make the views be actually created.

The front view is actually the main view and the isometric view is added to the predefined configuration.

The ISO and ANSI standards are independent from the angle projection method.